C# SolidWorks 二次开发 API —创建异型孔特征

之前有网友咨询过如何创建异型孔特征,今天我们来看下如何实现：

异孔特征中参数比较多，想要用的好还是要看API的帮助文档：

下面是简单的一个代码：

        /// <summary>
        /// 插入异形孔特征
        /// </summary>
        /// <param name="sender"></param>
        /// <param name="e"></param>
        private void btnInsertHole_Click(object sender, EventArgs e)
        {
            SldWorks swApp = PStandAlone.GetSolidWorks();

            AddHoleForThisPoint("holePoints", 10, "异型孔测试");
        }

        /// <summary>
        /// 插入简单孔特征
        /// </summary>
        /// <param name="sketchName">草图名称</param>
        /// <param name="DiaSize">孔径</param>
        /// <param name="holeName">名称</param>
        public void AddHoleForThisPoint(string sketchName, double DiaSize, string holeName)
        {
            SldWorks SwApp;

            Feature swFeature;

            string fileName;
            long errors;
            long warnings;
            bool status;
            int SlotType;
            int HoleType;
            int StandardIndex;
            int FastenerTypeIndex;
            string SSize;
            short EndType;
            double ConvFactorLength;
            double ConvFactorAngle;
            double Diameter;
            double Depth;
            double Length;
            double ScrewFit;
            double DrillAngle;
            double NearCsinkDiameter;
            double NearCsinkAngle;
            double FarCsinkDiameter;
            double FarCsinkAngle;
            double Offset;
            string ThreadClass;
            double CounterBoreDiameter;
            double CounterBoreDepth;
            double HeadClearance;
            double BotCsinkDiameter;
            double BotCsinkAngle;
            WizardHoleFeatureData2 swWizardHoleFeatData;

            SldWorks swApp = PStandAlone.GetSolidWorks();

            ModelDoc2 swModel = (ModelDoc2)swApp.ActiveDoc;

            var swFeatureMgr = swModel.FeatureManager;

            var swModelDocExt = swModel.Extension;

            status = swModel.Extension.SelectByID2("Front Plane", "PLANE", 0, 0, 0, false, 0, null, 0);

            HoleType = (int)swWzdGeneralHoleTypes_e.swWzdLegacy;
            StandardIndex = -1;
            FastenerTypeIndex = -1;
            SSize = "";
            EndType = (int)swEndConditions_e.swEndCondThroughAll;
            ConvFactorAngle = -1;

            Diameter = DiaSize / 1000;

            Depth = -1;
            Length = -1;

            CounterBoreDiameter = 0;    // Value1
            CounterBoreDepth = 0;   // Value2
            HeadClearance = -1;                              // Value3
            ScrewFit = -1;                                   // Value4
            DrillAngle = -1;                                 // Value5
            NearCsinkDiameter = -1;                          // Value6
            NearCsinkAngle = -1;                             // Value7
            BotCsinkDiameter = -1;                           // Value8
            BotCsinkAngle = -1;                              // Value9
            FarCsinkDiameter = -1;                           // Value10
            FarCsinkAngle = -1;                              // Value11
            Offset = -1;                                     // Value12
            ThreadClass = "";

            swFeature = swFeatureMgr.HoleWizard5(HoleType, StandardIndex, FastenerTypeIndex, SSize, EndType, Diameter, Depth, Length, CounterBoreDiameter, CounterBoreDepth, HeadClearance, ScrewFit, DrillAngle, NearCsinkDiameter, NearCsinkAngle, BotCsinkDiameter, BotCsinkAngle, FarCsinkDiameter, FarCsinkAngle, Offset, ThreadClass, false, false, false, false, false, false);

            Feature holeFeature = (Feature)swFeature.GetFirstSubFeature();

            Feature sizeFeature = (Feature)holeFeature.GetNextSubFeature();

            holeFeature.Select2(false, 0);
            swModel.EditSketch();

            swModel.ClearSelection2(true);
            status = swModel.Extension.SelectByID2("Point1", "SKETCHPOINT", 0, 0, 0, false, 0, null, 0);

            status = swModel.Extension.SelectByID2("Point1@" + sketchName, "EXTSKETCHPOINT", 0, 0, 0, true, 0, null, 0);

            swModel.SketchAddConstraints("sgCOINCIDENT");
            swModel.ClearSelection2(true);

            swModel.ClearSelection2(true);
            swModel.SketchManager.InsertSketch(true);

            holeFeature.Name = holeName + "-点位";
            sizeFeature.Name = holeName + "-尺寸";

            swFeature.Name = holeName;

            status = swModel.Extension.SelectByID2(holeName, "BODYFEATURE", 0, 0, 0, false, 4, null, 0);
            status = swModel.Extension.SelectByID2(sketchName, "SKETCH", 0, 0, 0, true, 64, null, 0);

            swFeature = swModel.FeatureManager.FeatureSketchDrivenPattern(true, false)
            ;

            swFeature.Name = "阵列-" + holeName;
        }
   

运行完之后 效果如下图，我打的是简单直孔，如果要打螺纹孔这些需要细看api参数。

可在此下载源码：https://gitee.com/painezeng/CSharpAndSolidWorks

posted @
2023-03-15 12:20 
painezeng  阅读(
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